- damping_threshold_factor1000If previous iterations's slip is below the slip tolerance, only damp a slip reversal if the slip magnitude is greater than than this factor times the old slip.
Default:1000
C++ Type:double
Unit:(no unit assumed)
Controllable:No
Description:If previous iterations's slip is below the slip tolerance, only damp a slip reversal if the slip magnitude is greater than than this factor times the old slip.
- debug_outputFalseOutput detailed debugging information
Default:False
C++ Type:bool
Controllable:No
Description:Output detailed debugging information
- max_iterative_slip1.79769e+308Maximum iterative slip
Default:1.79769e+308
C++ Type:double
Unit:(no unit assumed)
Controllable:No
Description:Maximum iterative slip
- min_damping0Minimum value of computed damping. Damping lower than this will result in an exception being thrown and cutting the time step
Default:0
C++ Type:double
Unit:(no unit assumed)
Controllable:No
Description:Minimum value of computed damping. Damping lower than this will result in an exception being thrown and cutting the time step
- min_damping_factor0Minimum permissible value for damping factor
Default:0
C++ Type:double
Unit:(no unit assumed)
Controllable:No
Description:Minimum permissible value for damping factor
- primaryIDs of the primary surfaces for which slip reversals should be damped
C++ Type:std::vector<BoundaryName>
Controllable:No
Description:IDs of the primary surfaces for which slip reversals should be damped
- secondaryIDs of the secondary surfaces for which slip reversals should be damped
C++ Type:std::vector<BoundaryName>
Controllable:No
Description:IDs of the secondary surfaces for which slip reversals should be damped
ContactSlipDamper
Damp the iterative solution to minimize oscillations in frictional contact constriants between nonlinear iterations
Description
This damper minimizes the oscillations that are inherent in the solution of frictional contact problems by limiting the change in contact state from one nonlinear iteration to the next. This is designed specifically to work with node/face mechanical contact enforced using MechanicalContactConstraint.
This damper specifically addresses reversals in the slip direction from one nonlinear iteration to the next. If a node that is in contact slips farther than it should during a given nonlinear iteration, the resulting residual will cause that node to slip back in the opposite direction in the next nonlinear iteration. If that slip in the opposite direction in this next nonlinear iteration is large enough that it causes the node to slip past the original contact point, it can be extremely difficult to obtain a converged solution because the node keeps slipping back and forth past that original contact point during each nonlinear iteration.
This damper mitigates this problem by scaling back the nonlinear solution update to limit the amount of slip experienced by nodes that are slipping in a direction opposite to the slip direction in the previous nonlinear iteration. For each node in this situation, a scale factor that would bring the node back to its original position is computed, and the minimum value for all such nodes is taken as the overall scale factor. For a simulation with many nodes in contact, this can result initially in small damping factors, but over the course of iterations as the converged solution is approached, the damping factor will typically increase.
The following optional parameters can be used to adjust the behavior of this damper:
min_damping_factorsets a minimum value for the damping. Setting this to a number larger than 0 can permit some amount of excess slip reversals to avoid having the solution getting stuck with extremely small damping factors.max_iterative_slipallows the damper to also limit the amount of slip that can occur during a nonlinear iteration, in addition to limiting slip reversals. This is prescribed in the length units of the model.damping_threshold_factoraffects the slip reversal limiting behavior of this damper when the magnitude of the slip is small. If the amount of slip is small, the node is likely actually in a sticking state, and simply moving within the limits permitted by the penalty factor. This factor specifies the threshold slip, computed as a multiplier on the limit imposed by the penalty factor, at which the damper will start to limit slip reversals. Setting it to larger numbers will make this damper have less effect on nodes will small amounts of slip.
In addition to limiting the nonlinear solution step, this damper also prints out some useful diagnostic information to the output stream, including statistics on the numbers of nodes in various contact states.
Finally, it should be noted that although this damper is primarily intended to be used with frictional contact, it can be useful for frictionless contact because of its ability to limit the maximum amount of slip.
Example Input Syntax
[Dampers<<<{"href": "../../syntax/Dampers/index.html"}>>>]
[./contact_slip]
type = ContactSlipDamper<<<{"description": "Damp the iterative solution to minimize oscillations in frictional contact constriants between nonlinear iterations", "href": "ContactSlipDamper.html"}>>>
secondary<<<{"description": "IDs of the secondary surfaces for which slip reversals should be damped"}>>> = 3
primary<<<{"description": "IDs of the primary surfaces for which slip reversals should be damped"}>>> = 2
[../]
[]Input Parameters
- control_tagsAdds user-defined labels for accessing object parameters via control logic.
C++ Type:std::vector<std::string>
Controllable:No
Description:Adds user-defined labels for accessing object parameters via control logic.
- enableTrueSet the enabled status of the MooseObject.
Default:True
C++ Type:bool
Controllable:Yes
Description:Set the enabled status of the MooseObject.
Advanced Parameters
Input Files
- (modules/contact/test/tests/verification/hertz_cyl/half_symm_q4/hertz_cyl_half_1deg_template3.i)
- (modules/contact/test/tests/frictional/single_point_2d/single_point_2d_predictor.i)
- (modules/contact/test/tests/verification/hertz_cyl/half_symm_q8/hertz_cyl_half_1deg_template3.i)
- (modules/contact/examples/3d_berkovich/indenter_berkovich_friction.i)
- (modules/contact/test/tests/frictional/sliding_elastic_blocks_2d/sliding_elastic_blocks_2d_tp.i)
- (modules/contact/test/tests/frictional/single_point_2d/single_point_2d_tp.i)
- (modules/contact/test/tests/frictional/single_point_2d/single_point_2d.i)
- (modules/combined/test/tests/break_mesh_interface_contact/break_mesh_interface_contact.i)
- (modules/contact/test/tests/hertz_spherical/hertz_contact_hex20.i)
- (modules/contact/examples/2d_indenter/indenter_rz_nodeface_friction.i)
- (modules/contact/test/tests/frictional/sliding_elastic_blocks_2d/sliding_elastic_blocks_2d.i)
- (modules/contact/test/tests/verification/patch_tests/single_pnt_2d/single_point_2d_frictional.i)
(modules/contact/test/tests/frictional/sliding_elastic_blocks_2d/sliding_elastic_blocks_2d.i)
[Mesh]
file = sliding_elastic_blocks_2d.e
[]
[GlobalParams]
volumetric_locking_correction = false
displacements = 'disp_x disp_y'
[]
[AuxVariables]
[./penetration]
[../]
[./saved_x]
[../]
[./saved_y]
[../]
[./diag_saved_x]
[../]
[./diag_saved_y]
[../]
[./inc_slip_x]
[../]
[./inc_slip_y]
[../]
[./accum_slip_x]
[../]
[./accum_slip_y]
[../]
[./accum_slip]
[../]
[./tang_force_x]
[../]
[./tang_force_y]
[../]
[]
[Functions]
[./vertical_movement]
type = ParsedFunction
expression = -t
[../]
[]
[Physics/SolidMechanics/QuasiStatic]
[./all]
add_variables = true
strain = FINITE
save_in = 'saved_x saved_y'
diag_save_in = 'diag_saved_x diag_saved_y'
[../]
[]
[AuxKernels]
[./inc_slip_x]
type = PenetrationAux
variable = inc_slip_x
quantity = incremental_slip_x
boundary = 3
paired_boundary = 2
[../]
[./inc_slip_y]
type = PenetrationAux
variable = inc_slip_y
quantity = incremental_slip_y
boundary = 3
paired_boundary = 2
[../]
[./accum_slip]
type = PenetrationAux
variable = accum_slip
execute_on = timestep_end
quantity = accumulated_slip
boundary = 3
paired_boundary = 2
[../]
[./tangential_force_x]
type = PenetrationAux
variable = tang_force_x
execute_on = timestep_end
quantity = tangential_force_x
boundary = 3
paired_boundary = 2
[../]
[./tangential_force_y]
type = PenetrationAux
variable = tang_force_y
execute_on = timestep_end
quantity = tangential_force_y
boundary = 3
paired_boundary = 2
[../]
[./accum_slip_x]
type = AccumulateAux
variable = accum_slip_x
accumulate_from_variable = inc_slip_x
execute_on = timestep_end
[../]
[./accum_slip_y]
type = AccumulateAux
variable = accum_slip_y
accumulate_from_variable = inc_slip_y
execute_on = timestep_end
[../]
[./penetration]
type = PenetrationAux
variable = penetration
boundary = 3
paired_boundary = 2
[../]
[]
[Postprocessors]
[./bot_react_x]
type = NodalSum
variable = saved_x
boundary = 1
[../]
[./bot_react_y]
type = NodalSum
variable = saved_y
boundary = 1
[../]
[./top_react_x]
type = NodalSum
variable = saved_x
boundary = 4
[../]
[./top_react_y]
type = NodalSum
variable = saved_y
boundary = 4
[../]
[./ref_resid_x]
type = NodalL2Norm
execute_on = timestep_end
variable = saved_x
[../]
[./ref_resid_y]
type = NodalL2Norm
execute_on = timestep_end
variable = saved_y
[../]
[]
[BCs]
[./left_x]
type = DirichletBC
variable = disp_x
boundary = 1
value = 0.0
[../]
[./left_y]
type = DirichletBC
variable = disp_y
boundary = 1
value = 0.0
[../]
[./right_x]
type = DirichletBC
variable = disp_x
boundary = 4
value = -0.005
[../]
[./right_y]
type = FunctionDirichletBC
variable = disp_y
boundary = 4
function = vertical_movement
[../]
[]
[Materials]
[./left]
type = ComputeIsotropicElasticityTensor
block = '1'
youngs_modulus = 1.0e7
poissons_ratio = 0.3
[../]
[./right]
type = ComputeIsotropicElasticityTensor
block = '2'
youngs_modulus = 1.0e6
poissons_ratio = 0.3
[../]
[./stress]
type = ComputeFiniteStrainElasticStress
block = '1 2'
[../]
[]
[Preconditioning]
[./SMP]
type = SMP
full = true
[../]
[]
[Executioner]
type = Transient
solve_type = 'PJFNK'
petsc_options_iname = '-pc_type -pc_factor_mat_solver_type'
petsc_options_value = 'lu superlu_dist'
line_search = 'none'
l_max_its = 100
nl_max_its = 1000
dt = 0.01
end_time = 0.05
num_steps = 1000
nl_rel_tol = 1e-16
nl_abs_tol = 1e-09
dtmin = 0.01
l_tol = 1e-3
[./Predictor]
type = SimplePredictor
scale = 1.0
[../]
[]
[Outputs]
file_base = sliding_elastic_blocks_2d_out
print_linear_residuals = true
perf_graph = true
[./exodus]
type = Exodus
elemental_as_nodal = true
[../]
[./console]
type = Console
max_rows = 5
[../]
[]
[Contact]
[./leftright]
secondary = 3
primary = 2
model = coulomb
friction_coefficient = '0.25'
penalty = 1e6
[../]
[]
[Dampers]
[./contact_slip]
type = ContactSlipDamper
secondary = 3
primary = 2
[../]
[]
(modules/contact/test/tests/verification/hertz_cyl/half_symm_q4/hertz_cyl_half_1deg_template3.i)
[GlobalParams]
order = FIRST
family = LAGRANGE
volumetric_locking_correction = true
displacements = 'disp_x disp_y'
[]
[Mesh]
file = hertz_cyl_half_1deg.e
[]
[Problem]
type = ReferenceResidualProblem
extra_tag_vectors = 'ref'
reference_vector = 'ref'
[]
[Variables]
[./disp_x]
[../]
[./disp_y]
[../]
[]
[AuxVariables]
[./stress_xx]
order = CONSTANT
family = MONOMIAL
[../]
[./stress_yy]
order = CONSTANT
family = MONOMIAL
[../]
[./stress_xy]
order = CONSTANT
family = MONOMIAL
[../]
[./saved_x]
[../]
[./saved_y]
[../]
[./diag_saved_x]
[../]
[./diag_saved_y]
[../]
[./inc_slip_x]
[../]
[./inc_slip_y]
[../]
[./accum_slip_x]
[../]
[./accum_slip_y]
[../]
[./tang_force_x]
[../]
[./tang_force_y]
[../]
[]
[Functions]
[./disp_ramp_vert]
type = PiecewiseLinear
x = '0. 1. 11.'
y = '0. -0.0020 -0.0020'
[../]
[./disp_ramp_horz]
type = PiecewiseLinear
x = '0. 1. 11.'
y = '0. 0.0 0.0014'
[../]
[]
[Kernels]
[./TensorMechanics]
use_displaced_mesh = true
extra_vector_tags = 'ref'
save_in = 'saved_x saved_y'
[../]
[]
[AuxKernels]
[./stress_xx]
type = RankTwoAux
rank_two_tensor = stress
variable = stress_xx
index_i = 0
index_j = 0
execute_on = timestep_end
[../]
[./stress_yy]
type = RankTwoAux
rank_two_tensor = stress
variable = stress_yy
index_i = 1
index_j = 1
execute_on = timestep_end
[../]
[./stress_xy]
type = RankTwoAux
rank_two_tensor = stress
variable = stress_xy
index_i = 0
index_j = 1
execute_on = timestep_end
[../]
[./inc_slip_x]
type = PenetrationAux
variable = inc_slip_x
execute_on = timestep_end
boundary = 3
paired_boundary = 2
[../]
[./inc_slip_y]
type = PenetrationAux
variable = inc_slip_y
execute_on = timestep_end
boundary = 3
paired_boundary = 2
[../]
[./accum_slip_x]
type = PenetrationAux
variable = accum_slip_x
execute_on = timestep_end
boundary = 3
paired_boundary = 2
[../]
[./accum_slip_y]
type = PenetrationAux
variable = accum_slip_y
execute_on = timestep_end
boundary = 3
paired_boundary = 2
[../]
[./tang_force_x]
type = PenetrationAux
variable = tang_force_x
quantity = tangential_force_x
boundary = 3
paired_boundary = 2
[../]
[./tang_force_y]
type = PenetrationAux
variable = tang_force_y
quantity = tangential_force_y
boundary = 3
paired_boundary = 2
[../]
[./penetration]
type = PenetrationAux
variable = penetration
boundary = 3
paired_boundary = 2
[../]
[]
[Postprocessors]
[./bot_react_x]
type = NodalSum
variable = saved_x
boundary = 1
[../]
[./bot_react_y]
type = NodalSum
variable = saved_y
boundary = 1
[../]
[./top_react_x]
type = NodalSum
variable = saved_x
boundary = 4
[../]
[./top_react_y]
type = NodalSum
variable = saved_y
boundary = 4
[../]
[./disp_x226]
type = NodalVariableValue
nodeid = 225
variable = disp_x
[../]
[./disp_y226]
type = NodalVariableValue
nodeid = 225
variable = disp_y
[../]
[./_dt]
type = TimestepSize
[../]
[./num_lin_it]
type = NumLinearIterations
[../]
[./num_nonlin_it]
type = NumNonlinearIterations
[../]
[]
[BCs]
[./side_x]
type = DirichletBC
variable = disp_y
boundary = '1 2'
value = 0.0
[../]
[./bot_y]
type = DirichletBC
variable = disp_x
boundary = '1 2'
value = 0.0
[../]
[./top_y_disp]
type = FunctionDirichletBC
variable = disp_y
boundary = 4
function = disp_ramp_vert
[../]
[./top_x_disp]
type = FunctionDirichletBC
variable = disp_x
boundary = 4
function = disp_ramp_horz
[../]
[]
[Materials]
[./stuff1_elas_tens]
type = ComputeIsotropicElasticityTensor
block = '1'
youngs_modulus = 1e10
poissons_ratio = 0.0
[../]
[./stuff1_strain]
type = ComputeFiniteStrain
block = '1'
[../]
[./stuff1_stress]
type = ComputeFiniteStrainElasticStress
block = '1'
[../]
[./stuff2_elas_tens]
type = ComputeIsotropicElasticityTensor
block = '2'
youngs_modulus = 1e6
poissons_ratio = 0.3
[../]
[./stuff2_strain]
type = ComputeFiniteStrain
block = '2'
[../]
[./stuff2_stress]
type = ComputeFiniteStrainElasticStress
block = '2'
[../]
[./stuff3_elas_tens]
type = ComputeIsotropicElasticityTensor
block = '3'
youngs_modulus = 1e6
poissons_ratio = 0.3
[../]
[./stuff3_strain]
type = ComputeFiniteStrain
block = '3'
[../]
[./stuff3_stress]
type = ComputeFiniteStrainElasticStress
block = '3'
[../]
[./stuff4_elas_tens]
type = ComputeIsotropicElasticityTensor
block = '4'
youngs_modulus = 1e6
poissons_ratio = 0.3
[../]
[./stuff4_strain]
type = ComputeFiniteStrain
block = '4'
[../]
[./stuff4_stress]
type = ComputeFiniteStrainElasticStress
block = '4'
[../]
[./stuff5_elas_tens]
type = ComputeIsotropicElasticityTensor
block = '5'
youngs_modulus = 1e6
poissons_ratio = 0.3
[../]
[./stuff5_strain]
type = ComputeFiniteStrain
block = '5'
[../]
[./stuff5_stress]
type = ComputeFiniteStrainElasticStress
block = '5'
[../]
[./stuff6_elas_tens]
type = ComputeIsotropicElasticityTensor
block = '6'
youngs_modulus = 1e6
poissons_ratio = 0.3
[../]
[./stuff6_strain]
type = ComputeFiniteStrain
block = '6'
[../]
[./stuff6_stress]
type = ComputeFiniteStrainElasticStress
block = '6'
[../]
[./stuff7_elas_tens]
type = ComputeIsotropicElasticityTensor
block = '7'
youngs_modulus = 1e6
poissons_ratio = 0.3
[../]
[./stuff7_strain]
type = ComputeFiniteStrain
block = '7'
[../]
[./stuff7_stress]
type = ComputeFiniteStrainElasticStress
block = '7'
[../]
[]
[Executioner]
type = Transient
#Preconditioned JFNK (default)
solve_type = 'PJFNK'
petsc_options_iname = '-pc_type -pc_factor_mat_solver_type'
petsc_options_value = 'lu superlu_dist'
line_search = 'none'
nl_abs_tol = 1e-7
nl_rel_tol = 1e-6
l_max_its = 100
nl_max_its = 200
start_time = 0.0
end_time = 2.0
l_tol = 5e-4
dt = 0.1
dtmin = 0.1
[]
[Preconditioning]
[./SMP]
type = SMP
full = true
[../]
[]
[VectorPostprocessors]
[./x_disp]
type = NodalValueSampler
variable = disp_x
boundary = '3 4'
sort_by = id
[../]
[./y_disp]
type = NodalValueSampler
variable = disp_y
boundary = '3 4'
sort_by = id
[../]
[./cont_press]
type = NodalValueSampler
variable = contact_pressure
boundary = '3'
sort_by = id
[../]
[]
[Outputs]
print_linear_residuals = true
perf_graph = true
[./exodus]
type = Exodus
elemental_as_nodal = true
[../]
[./console]
type = Console
max_rows = 5
[../]
[./chkfile]
type = CSV
show = 'x_disp y_disp cont_press'
start_time = 0.9
execute_vector_postprocessors_on = timestep_end
[../]
[./chkfile2]
type = CSV
show = 'bot_react_x bot_react_y disp_x226 disp_y226 top_react_x top_react_y'
start_time = 0.9
execute_vector_postprocessors_on = timestep_end
[../]
[./outfile]
type = CSV
delimiter = ' '
execute_vector_postprocessors_on = none
[../]
[]
[Contact]
[./interface]
primary = 2
secondary = 3
model = coulomb
friction_coefficient = 0.0
formulation = penalty
normalize_penalty = true
tangential_tolerance = 1e-3
penalty = 1e+9
[../]
[]
[Dampers]
[./contact_slip]
type = ContactSlipDamper
primary = '2'
secondary = '3'
[../]
[]
(modules/contact/test/tests/frictional/single_point_2d/single_point_2d_predictor.i)
[Mesh]
file = single_point_2d.e
[]
[GlobalParams]
displacements = 'disp_x disp_y'
volumetric_locking_correction = false
[]
[AuxVariables]
[./penetration]
[../]
[./saved_x]
[../]
[./saved_y]
[../]
[./diag_saved_x]
[../]
[./diag_saved_y]
[../]
[./inc_slip_x]
[../]
[./inc_slip_y]
[../]
[./accum_slip_x]
[../]
[./accum_slip_y]
[../]
[]
[Functions]
[./horizontal_movement]
type = ParsedFunction
expression = t
[../]
[]
[Physics/SolidMechanics/QuasiStatic]
[./all]
add_variables = true
strain = FINITE
save_in = 'saved_x saved_y'
diag_save_in = 'diag_saved_x diag_saved_y'
[../]
[]
[AuxKernels]
[./incslip_x]
type = PenetrationAux
variable = inc_slip_x
quantity = incremental_slip_x
boundary = 3
paired_boundary = 2
[../]
[./incslip_y]
type = PenetrationAux
variable = inc_slip_y
quantity = incremental_slip_y
boundary = 3
paired_boundary = 2
[../]
[./accum_slip_x]
type = AccumulateAux
variable = accum_slip_x
accumulate_from_variable = inc_slip_x
execute_on = timestep_end
[../]
[./accum_slip_y]
type = AccumulateAux
variable = accum_slip_y
accumulate_from_variable = inc_slip_y
execute_on = timestep_end
[../]
[./penetration]
type = PenetrationAux
variable = penetration
boundary = 3
paired_boundary = 2
[../]
[]
[BCs]
[./botx]
type = DirichletBC
variable = disp_x
boundary = 1
value = 0.0
[../]
[./boty]
type = DirichletBC
variable = disp_y
boundary = 1
value = 0.0
[../]
[./botx2]
type = DirichletBC
variable = disp_x
boundary = 2
value = 0.0
[../]
[./boty2]
type = DirichletBC
variable = disp_y
boundary = 2
value = 0.0
[../]
[./topx]
type = FunctionDirichletBC
variable = disp_x
boundary = 4
function = horizontal_movement
[../]
[./topy]
type = DirichletBC
variable = disp_y
boundary = 4
value = -0.005
[../]
[]
[Materials]
[./bottom]
type = ComputeIsotropicElasticityTensor
block = '1'
youngs_modulus = 1.0e9
poissons_ratio = 0.3
[../]
[./stress]
type = ComputeFiniteStrainElasticStress
block = '1 2'
[../]
[./top]
type = ComputeIsotropicElasticityTensor
block = '2'
youngs_modulus = 1.0e6
poissons_ratio = 0.3
[../]
[]
[Postprocessors]
[./bot_react_x]
type = NodalSum
variable = saved_x
boundary = 1
[../]
[./bot_react_y]
type = NodalSum
variable = saved_y
boundary = 1
[../]
[./top_react_x]
type = NodalSum
variable = saved_x
boundary = 4
[../]
[./top_react_y]
type = NodalSum
variable = saved_y
boundary = 4
[../]
[./ref_resid_x]
type = NodalL2Norm
execute_on = timestep_end
variable = saved_x
[../]
[./ref_resid_y]
type = NodalL2Norm
execute_on = timestep_end
variable = saved_y
[../]
[]
[Executioner]
type = Transient
solve_type = 'PJFNK'
petsc_options_iname = '-pc_type -pc_factor_mat_solver_type'
petsc_options_value = 'lu superlu_dist'
line_search = 'none'
l_max_its = 100
nl_max_its = 200
dt = 0.001
end_time = 0.01
num_steps = 1000
nl_rel_tol = 1e-8
nl_abs_tol = 1e-8
dtmin = 0.001
l_tol = 1e-3
[./Predictor]
type = SimplePredictor
scale = 1.0
[../]
[]
[Outputs]
exodus = true
print_linear_residuals = true
perf_graph = true
[./console]
type = Console
max_rows = 5
[../]
[]
[Contact]
[./leftright]
primary = 2
secondary = 3
model = coulomb
friction_coefficient = '0.25'
[../]
[]
[Dampers]
[./contact_slip]
type = ContactSlipDamper
primary = '2'
secondary = '3'
[../]
[]
(modules/contact/test/tests/verification/hertz_cyl/half_symm_q8/hertz_cyl_half_1deg_template3.i)
[GlobalParams]
order = SECOND
volumetric_locking_correction = false
displacements = 'disp_x disp_y'
[]
[Mesh]
file = hertz_cyl_half_1deg.e
[]
[Problem]
type = ReferenceResidualProblem
extra_tag_vectors = 'ref'
reference_vector = 'ref'
[]
[Variables]
[./disp_x]
[../]
[./disp_y]
[../]
[]
[AuxVariables]
[./stress_xx]
order = CONSTANT
family = MONOMIAL
[../]
[./stress_yy]
order = CONSTANT
family = MONOMIAL
[../]
[./stress_xy]
order = CONSTANT
family = MONOMIAL
[../]
[./saved_x]
[../]
[./saved_y]
[../]
[./diag_saved_x]
[../]
[./diag_saved_y]
[../]
[./inc_slip_x]
[../]
[./inc_slip_y]
[../]
[./accum_slip_x]
[../]
[./accum_slip_y]
[../]
[./tang_force_x]
[../]
[./tang_force_y]
[../]
[]
[Functions]
[./disp_ramp_vert]
type = PiecewiseLinear
x = '0. 1. 11.'
y = '0. -0.0020 -0.0020'
[../]
[./disp_ramp_horz]
type = PiecewiseLinear
x = '0. 1. 11.'
y = '0. 0.0 0.0014'
[../]
[]
[Kernels]
[./TensorMechanics]
use_displaced_mesh = true
save_in = 'saved_x saved_y'
extra_vector_tags = 'ref'
[../]
[]
[AuxKernels]
[./stress_xx]
type = RankTwoAux
rank_two_tensor = stress
variable = stress_xx
index_i = 0
index_j = 0
execute_on = timestep_end
[../]
[./stress_yy]
type = RankTwoAux
rank_two_tensor = stress
variable = stress_yy
index_i = 1
index_j = 1
execute_on = timestep_end
[../]
[./stress_xy]
type = RankTwoAux
rank_two_tensor = stress
variable = stress_xy
index_i = 0
index_j = 1
execute_on = timestep_end
[../]
[./inc_slip_x]
type = PenetrationAux
variable = inc_slip_x
execute_on = timestep_end
boundary = 3
paired_boundary = 2
[../]
[./inc_slip_y]
type = PenetrationAux
variable = inc_slip_y
execute_on = timestep_end
boundary = 3
paired_boundary = 2
[../]
[./accum_slip_x]
type = PenetrationAux
variable = accum_slip_x
execute_on = timestep_end
boundary = 3
paired_boundary = 2
[../]
[./accum_slip_y]
type = PenetrationAux
variable = accum_slip_y
execute_on = timestep_end
boundary = 3
paired_boundary = 2
[../]
[./tang_force_x]
type = PenetrationAux
variable = tang_force_x
quantity = tangential_force_x
boundary = 3
paired_boundary = 2
[../]
[./tang_force_y]
type = PenetrationAux
variable = tang_force_y
quantity = tangential_force_y
boundary = 3
paired_boundary = 2
[../]
[./penetration]
type = PenetrationAux
variable = penetration
boundary = 3
paired_boundary = 2
[../]
[]
[Postprocessors]
[./bot_react_x]
type = NodalSum
variable = saved_x
boundary = 1
[../]
[./bot_react_y]
type = NodalSum
variable = saved_y
boundary = 1
[../]
[./top_react_x]
type = NodalSum
variable = saved_x
boundary = 4
[../]
[./top_react_y]
type = NodalSum
variable = saved_y
boundary = 4
[../]
[./disp_x639]
type = NodalVariableValue
nodeid = 638
variable = disp_x
[../]
[./disp_y639]
type = NodalVariableValue
nodeid = 638
variable = disp_y
[../]
[./_dt]
type = TimestepSize
[../]
[./num_lin_it]
type = NumLinearIterations
[../]
[./num_nonlin_it]
type = NumNonlinearIterations
[../]
[]
[BCs]
[./side_x]
type = DirichletBC
variable = disp_y
boundary = '1 2'
value = 0.0
[../]
[./bot_y]
type = DirichletBC
variable = disp_x
boundary = '1 2'
value = 0.0
[../]
[./top_y_disp]
type = FunctionDirichletBC
variable = disp_y
boundary = 4
function = disp_ramp_vert
[../]
[./top_x_disp]
type = FunctionDirichletBC
variable = disp_x
boundary = 4
function = disp_ramp_horz
[../]
[]
[Materials]
[./stuff1_elas_tens]
type = ComputeIsotropicElasticityTensor
block = '1'
youngs_modulus = 1e10
poissons_ratio = 0.0
[../]
[./stuff1_strain]
type = ComputeFiniteStrain
block = '1'
[../]
[./stuff1_stress]
type = ComputeFiniteStrainElasticStress
block = '1'
[../]
[./stuff2_elas_tens]
type = ComputeIsotropicElasticityTensor
block = '2'
youngs_modulus = 1e6
poissons_ratio = 0.3
[../]
[./stuff2_strain]
type = ComputeFiniteStrain
block = '2'
[../]
[./stuff2_stress]
type = ComputeFiniteStrainElasticStress
block = '2'
[../]
[./stuff3_elas_tens]
type = ComputeIsotropicElasticityTensor
block = '3'
youngs_modulus = 1e6
poissons_ratio = 0.3
[../]
[./stuff3_strain]
type = ComputeFiniteStrain
block = '3'
[../]
[./stuff3_stress]
type = ComputeFiniteStrainElasticStress
block = '3'
[../]
[./stuff4_elas_tens]
type = ComputeIsotropicElasticityTensor
block = '4'
youngs_modulus = 1e6
poissons_ratio = 0.3
[../]
[./stuff4_strain]
type = ComputeFiniteStrain
block = '4'
[../]
[./stuff4_stress]
type = ComputeFiniteStrainElasticStress
block = '4'
[../]
[./stuff5_elas_tens]
type = ComputeIsotropicElasticityTensor
block = '5'
youngs_modulus = 1e6
poissons_ratio = 0.3
[../]
[./stuff5_strain]
type = ComputeFiniteStrain
block = '5'
[../]
[./stuff5_stress]
type = ComputeFiniteStrainElasticStress
block = '5'
[../]
[./stuff6_elas_tens]
type = ComputeIsotropicElasticityTensor
block = '6'
youngs_modulus = 1e6
poissons_ratio = 0.3
[../]
[./stuff6_strain]
type = ComputeFiniteStrain
block = '6'
[../]
[./stuff6_stress]
type = ComputeFiniteStrainElasticStress
block = '6'
[../]
[./stuff7_elas_tens]
type = ComputeIsotropicElasticityTensor
block = '7'
youngs_modulus = 1e6
poissons_ratio = 0.3
[../]
[./stuff7_strain]
type = ComputeFiniteStrain
block = '7'
[../]
[./stuff7_stress]
type = ComputeFiniteStrainElasticStress
block = '7'
[../]
[]
[Executioner]
type = Transient
solve_type = 'PJFNK'
petsc_options_iname = '-pc_type -pc_factor_mat_solver_type'
petsc_options_value = 'lu superlu_dist'
line_search = 'none'
nl_abs_tol = 1e-7
nl_rel_tol = 1e-6
l_max_its = 100
nl_max_its = 200
start_time = 0.0
end_time = 2.0
l_tol = 5e-4
dt = 0.1
dtmin = 0.1
[]
[Preconditioning]
[./SMP]
type = SMP
full = true
[../]
[]
[VectorPostprocessors]
[./x_disp]
type = NodalValueSampler
variable = disp_x
boundary = '3 4'
sort_by = id
[../]
[./y_disp]
type = NodalValueSampler
variable = disp_y
boundary = '3 4'
sort_by = id
[../]
[./cont_press]
type = NodalValueSampler
variable = contact_pressure
boundary = '3'
sort_by = id
[../]
[]
[Outputs]
print_linear_residuals = true
perf_graph = true
[./exodus]
type = Exodus
elemental_as_nodal = true
[../]
[./console]
type = Console
max_rows = 5
[../]
[./chkfile]
type = CSV
show = 'x_disp y_disp cont_press'
start_time = 0.9
execute_vector_postprocessors_on = timestep_end
[../]
[./chkfile2]
type = CSV
show = 'bot_react_x bot_react_y disp_x639 disp_y639 top_react_x top_react_y'
start_time = 0.9
execute_vector_postprocessors_on = timestep_end
[../]
[./outfile]
type = CSV
delimiter = ' '
execute_vector_postprocessors_on = none
[../]
[]
[Contact]
[./interface]
primary = 2
secondary = 3
model = coulomb
friction_coefficient = 0.0
formulation = penalty
normalize_penalty = true
tangential_tolerance = 1e-3
penalty = 1e+9
[../]
[]
[Dampers]
[./contact_slip]
type = ContactSlipDamper
primary = '2'
secondary = '3'
[../]
[]
(modules/contact/examples/3d_berkovich/indenter_berkovich_friction.i)
[Mesh]
file = indenter.e
[]
[GlobalParams]
displacements = 'disp_x disp_y disp_z'
volumetric_locking_correction = true
order = FIRST
family = LAGRANGE
[]
[Variables]
[./disp_x]
[../]
[./disp_y]
[../]
[./disp_z]
[../]
[]
[AuxVariables]
[./saved_x]
[../]
[./saved_y]
[../]
[./saved_z]
[../]
[]
[AuxKernels]
[]
[Functions]
[./push_down]
type = ParsedFunction
expression = 'if(t < 1.5, -t, t-3.0)'
[../]
[]
[Physics/SolidMechanics/QuasiStatic]
[./all]
add_variables = true
strain = FINITE
block = '1 2'
use_automatic_differentiation = false
generate_output = 'stress_xx stress_xy stress_xz stress_yy stress_zz'
save_in = 'saved_x saved_y saved_z'
use_finite_deform_jacobian = true
[../]
[]
[BCs]
[./botz]
type = DirichletBC
variable = disp_z
boundary = 101
value = 0.0
[../]
[./boty]
type = DirichletBC
variable = disp_y
boundary = 101
value = 0.0
[../]
[./botx]
type = DirichletBC
variable = disp_x
boundary = 101
value = 0.0
[../]
[./boty111]
type = DirichletBC
variable = disp_y
boundary = 111
value = 0.0
[../]
[./botx111]
type = DirichletBC
variable = disp_x
boundary = 111
value = 0.0
[../]
[./topz]
type = FunctionDirichletBC
variable = disp_z
boundary = '201'
function = push_down
[../]
[./topy]
type = DirichletBC
variable = disp_y
boundary = 201
value = 0.0
[../]
[./topx]
type = DirichletBC
variable = disp_x
boundary = 201
value = 0.0
[../]
[]
[UserObjects]
[./slip_rate_gss]
type = CrystalPlasticitySlipRateGSS
variable_size = 48
slip_sys_file_name = input_slip_sys_bcc48.txt
num_slip_sys_flowrate_props = 2
flowprops = '1 48 0.0001 0.01'
uo_state_var_name = state_var_gss
slip_incr_tol = 10.0
block = 1
[../]
[./slip_resistance_gss]
type = CrystalPlasticitySlipResistanceGSS
variable_size = 48
uo_state_var_name = state_var_gss
block = 1
[../]
[./state_var_gss]
type = CrystalPlasticityStateVariable
variable_size = 48
groups = '0 24 48'
group_values = '900 1000' #120
uo_state_var_evol_rate_comp_name = state_var_evol_rate_comp_gss
scale_factor = 1.0
block = 1
[../]
[./state_var_evol_rate_comp_gss]
type = CrystalPlasticityStateVarRateComponentGSS
variable_size = 48
hprops = '1.4 1000 1200 2.5'
uo_slip_rate_name = slip_rate_gss
uo_state_var_name = state_var_gss
block = 1
[../]
[]
[Materials]
[./crysp]
type = FiniteStrainUObasedCP
block = 1
stol = 1e-2
tan_mod_type = exact
uo_slip_rates = 'slip_rate_gss'
uo_slip_resistances = 'slip_resistance_gss'
uo_state_vars = 'state_var_gss'
uo_state_var_evol_rate_comps = 'state_var_evol_rate_comp_gss'
maximum_substep_iteration = 25
[../]
[./elasticity_tensor]
type = ComputeElasticityTensorCP
block = 1
C_ijkl = '265190 113650 113650 265190 113650 265190 75769 75769 75760'
fill_method = symmetric9
[../]
[./elasticity_tensor_indenter]
type = ComputeIsotropicElasticityTensor
youngs_modulus = 1000000.0
poissons_ratio = 0.3
block = 2
[../]
[./stress_indenter]
type = ComputeFiniteStrainElasticStress
block = 2
[../]
[]
[Postprocessors]
[./stress_zz]
type = ElementAverageValue
variable = stress_zz
block = 1
[../]
[./resid_z]
type = NodalSum
variable = saved_z
boundary = 201
[../]
[./disp_z]
type = NodalExtremeValue
variable = disp_z
boundary = 201
[../]
[]
[Executioner]
type = Transient
solve_type = 'PJFNK'
petsc_options_iname = '-pc_type -pc_factor_mat_solver_type'
petsc_options_value = 'lu superlu_dist'
line_search = 'none'
l_max_its = 60
nl_max_its = 50
dt = 0.004
dtmin = 0.00001
end_time = 1.8
nl_rel_tol = 1e-8
nl_abs_tol = 1e-6 # 6 if no friction
l_tol = 1e-3
automatic_scaling = true
[]
[Outputs]
[./my_checkpoint]
type = Checkpoint
time_step_interval = 50
[../]
exodus = true
csv = true
print_linear_residuals = true
print_perf_log = true
[./console]
type = Console
max_rows = 5
[../]
[]
[Preconditioning]
[./smp]
type = SMP
full = true
[../]
[]
[Dampers]
[./contact_slip]
type = ContactSlipDamper
primary = '202'
secondary = '102'
[../]
[]
[Contact]
[./ind_base]
primary = 202
secondary = 102
model = coulomb
friction_coefficient = 0.4
normalize_penalty = true
formulation = tangential_penalty
penalty = 1e7
capture_tolerance = 0.0001
[../]
[]
(modules/contact/test/tests/frictional/sliding_elastic_blocks_2d/sliding_elastic_blocks_2d_tp.i)
[Mesh]
file = sliding_elastic_blocks_2d.e
[]
[GlobalParams]
volumetric_locking_correction = false
displacements = 'disp_x disp_y'
[]
[AuxVariables]
[./penetration]
[../]
[./saved_x]
[../]
[./saved_y]
[../]
[./diag_saved_x]
[../]
[./diag_saved_y]
[../]
[./inc_slip_x]
[../]
[./inc_slip_y]
[../]
[./accum_slip_x]
[../]
[./accum_slip_y]
[../]
[./accum_slip]
[../]
[./tang_force_x]
[../]
[./tang_force_y]
[../]
[]
[Functions]
[./vertical_movement]
type = ParsedFunction
expression = -t
[../]
[]
[Physics/SolidMechanics/QuasiStatic]
[./all]
add_variables = true
strain = FINITE
save_in = 'saved_x saved_y'
diag_save_in = 'diag_saved_x diag_saved_y'
[../]
[]
[AuxKernels]
[./inc_slip_x]
type = PenetrationAux
variable = inc_slip_x
quantity = incremental_slip_x
boundary = 3
paired_boundary = 2
[../]
[./inc_slip_y]
type = PenetrationAux
variable = inc_slip_y
quantity = incremental_slip_y
boundary = 3
paired_boundary = 2
[../]
[./accum_slip]
type = PenetrationAux
variable = accum_slip
execute_on = timestep_end
quantity = accumulated_slip
boundary = 3
paired_boundary = 2
[../]
[./tangential_force_x]
type = PenetrationAux
variable = tang_force_x
execute_on = timestep_end
quantity = tangential_force_x
boundary = 3
paired_boundary = 2
[../]
[./tangential_force_y]
type = PenetrationAux
variable = tang_force_y
execute_on = timestep_end
quantity = tangential_force_y
boundary = 3
paired_boundary = 2
[../]
[./accum_slip_x]
type = AccumulateAux
variable = accum_slip_x
accumulate_from_variable = inc_slip_x
execute_on = timestep_end
[../]
[./accum_slip_y]
type = AccumulateAux
variable = accum_slip_y
accumulate_from_variable = inc_slip_y
execute_on = timestep_end
[../]
[./penetration]
type = PenetrationAux
variable = penetration
boundary = 3
paired_boundary = 2
[../]
[]
[Postprocessors]
[./bot_react_x]
type = NodalSum
variable = saved_x
boundary = 1
[../]
[./bot_react_y]
type = NodalSum
variable = saved_y
boundary = 1
[../]
[./top_react_x]
type = NodalSum
variable = saved_x
boundary = 4
[../]
[./top_react_y]
type = NodalSum
variable = saved_y
boundary = 4
[../]
[./ref_resid_x]
type = NodalL2Norm
execute_on = timestep_end
variable = saved_x
[../]
[./ref_resid_y]
type = NodalL2Norm
execute_on = timestep_end
variable = saved_y
[../]
[]
[BCs]
[./left_x]
type = DirichletBC
variable = disp_x
boundary = 1
value = 0.0
[../]
[./left_y]
type = DirichletBC
variable = disp_y
boundary = 1
value = 0.0
[../]
[./right_x]
type = DirichletBC
variable = disp_x
boundary = 4
value = -0.005
[../]
[./right_y]
type = FunctionDirichletBC
variable = disp_y
boundary = 4
function = vertical_movement
[../]
[]
[Materials]
[./left]
type = ComputeIsotropicElasticityTensor
block = '1'
youngs_modulus = 1.0e7
poissons_ratio = 0.3
[../]
[./right]
type = ComputeIsotropicElasticityTensor
block = '2'
youngs_modulus = 1.0e6
poissons_ratio = 0.3
[../]
[./stress]
type = ComputeFiniteStrainElasticStress
block = '1 2'
[../]
[]
[Preconditioning]
[./SMP]
type = SMP
full = true
[../]
[]
[Executioner]
type = Transient
solve_type = 'PJFNK'
petsc_options_iname = '-pc_type -pc_factor_mat_solver_type'
petsc_options_value = 'lu superlu_dist'
line_search = 'none'
l_max_its = 100
nl_max_its = 1000
dt = 0.01
end_time = 0.05
num_steps = 1000
nl_rel_tol = 1e-16
nl_abs_tol = 1e-09
dtmin = 0.01
l_tol = 1e-3
[./Predictor]
type = SimplePredictor
scale = 1.0
[../]
[]
[Outputs]
print_linear_residuals = true
perf_graph = true
[./out]
type = Exodus
elemental_as_nodal = true
[../]
[./console]
type = Console
max_rows = 5
[../]
[]
[Contact]
[./leftright]
secondary = 3
primary = 2
model = coulomb
formulation = tangential_penalty
friction_coefficient = '0.25'
penalty = 1e6
[../]
[]
[Dampers]
[./contact_slip]
type = ContactSlipDamper
secondary = 3
primary = 2
[../]
[]
(modules/contact/test/tests/frictional/single_point_2d/single_point_2d_tp.i)
[Mesh]
file = single_point_2d.e
[]
[GlobalParams]
volumetric_locking_correction = false
displacements = 'disp_x disp_y'
[]
[AuxVariables]
[./penetration]
[../]
[./saved_x]
[../]
[./saved_y]
[../]
[./diag_saved_x]
[../]
[./diag_saved_y]
[../]
[./inc_slip_x]
[../]
[./inc_slip_y]
[../]
[./accum_slip_x]
[../]
[./accum_slip_y]
[../]
[]
[Functions]
[./horizontal_movement]
type = ParsedFunction
expression = t
[../]
[]
[Physics/SolidMechanics/QuasiStatic]
[./all]
add_variables = true
strain = FINITE
save_in = 'saved_x saved_y'
diag_save_in = 'diag_saved_x diag_saved_y'
[../]
[]
[AuxKernels]
[./incslip_x]
type = PenetrationAux
variable = inc_slip_x
quantity = incremental_slip_x
boundary = 3
paired_boundary = 2
[../]
[./incslip_y]
type = PenetrationAux
variable = inc_slip_y
quantity = incremental_slip_y
boundary = 3
paired_boundary = 2
[../]
[./accum_slip_x]
type = AccumulateAux
variable = accum_slip_x
accumulate_from_variable = inc_slip_x
execute_on = timestep_end
[../]
[./accum_slip_y]
type = AccumulateAux
variable = accum_slip_y
accumulate_from_variable = inc_slip_y
execute_on = timestep_end
[../]
[./penetration]
type = PenetrationAux
variable = penetration
boundary = 3
paired_boundary = 2
[../]
[]
[BCs]
[./botx]
type = DirichletBC
variable = disp_x
boundary = 1
value = 0.0
[../]
[./boty]
type = DirichletBC
variable = disp_y
boundary = 1
value = 0.0
[../]
[./botx2]
type = DirichletBC
variable = disp_x
boundary = 2
value = 0.0
[../]
[./boty2]
type = DirichletBC
variable = disp_y
boundary = 2
value = 0.0
[../]
[./topx]
type = FunctionDirichletBC
variable = disp_x
boundary = 4
function = horizontal_movement
[../]
[./topy]
type = DirichletBC
variable = disp_y
boundary = 4
value = -0.005
[../]
[]
[Materials]
[./bottom]
type = ComputeIsotropicElasticityTensor
block = '1'
youngs_modulus = 1.0e9
poissons_ratio = 0.3
[../]
[./stress]
type = ComputeFiniteStrainElasticStress
block = '1 2'
[../]
[./top]
type = ComputeIsotropicElasticityTensor
block = '2'
youngs_modulus = 1.0e6
poissons_ratio = 0.3
[../]
[]
[Postprocessors]
[./bot_react_x]
type = NodalSum
variable = saved_x
boundary = 1
[../]
[./bot_react_y]
type = NodalSum
variable = saved_y
boundary = 1
[../]
[./top_react_x]
type = NodalSum
variable = saved_x
boundary = 4
[../]
[./top_react_y]
type = NodalSum
variable = saved_y
boundary = 4
[../]
[./ref_resid_x]
type = NodalL2Norm
execute_on = timestep_end
variable = saved_x
[../]
[./ref_resid_y]
type = NodalL2Norm
execute_on = timestep_end
variable = saved_y
[../]
[]
[Executioner]
type = Transient
solve_type = 'PJFNK'
petsc_options_iname = '-pc_type -pc_factor_mat_solver_type'
petsc_options_value = 'lu superlu_dist'
line_search = 'none'
l_max_its = 100
nl_max_its = 200
dt = 0.001
end_time = 0.01
num_steps = 1000
nl_rel_tol = 1e-08
nl_abs_tol = 1e-08
dtmin = 0.001
l_tol = 1e-3
[]
[Outputs]
exodus = true
print_linear_residuals = true
perf_graph = true
[./console]
type = Console
max_rows = 5
[../]
[]
[Contact]
[./leftright]
primary = 2
secondary = 3
model = coulomb
friction_coefficient = '0.25'
formulation = tangential_penalty
penalty = 1e10
[../]
[]
[Dampers]
[./contact_slip]
type = ContactSlipDamper
primary = '2'
secondary = '3'
[../]
[]
(modules/contact/test/tests/frictional/single_point_2d/single_point_2d.i)
[Mesh]
file = single_point_2d.e
[]
[GlobalParams]
volumetric_locking_correction = false
displacements = 'disp_x disp_y'
[]
[AuxVariables]
[./penetration]
[../]
[./saved_x]
[../]
[./saved_y]
[../]
[./diag_saved_x]
[../]
[./diag_saved_y]
[../]
[./inc_slip_x]
[../]
[./inc_slip_y]
[../]
[./accum_slip_x]
[../]
[./accum_slip_y]
[../]
[]
[Functions]
[./horizontal_movement]
type = ParsedFunction
expression = t
[../]
[]
[Physics/SolidMechanics/QuasiStatic]
[./all]
add_variables = true
strain = FINITE
save_in = 'saved_x saved_y'
diag_save_in = 'diag_saved_x diag_saved_y'
[../]
[]
[AuxKernels]
[./incslip_x]
type = PenetrationAux
variable = inc_slip_x
quantity = incremental_slip_x
boundary = 3
paired_boundary = 2
[../]
[./incslip_y]
type = PenetrationAux
variable = inc_slip_y
quantity = incremental_slip_y
boundary = 3
paired_boundary = 2
[../]
[./accum_slip_x]
type = AccumulateAux
variable = accum_slip_x
accumulate_from_variable = inc_slip_x
execute_on = timestep_end
[../]
[./accum_slip_y]
type = AccumulateAux
variable = accum_slip_y
accumulate_from_variable = inc_slip_y
execute_on = timestep_end
[../]
[./penetration]
type = PenetrationAux
variable = penetration
boundary = 3
paired_boundary = 2
[../]
[]
[BCs]
[./botx]
type = DirichletBC
variable = disp_x
boundary = 1
value = 0.0
[../]
[./boty]
type = DirichletBC
variable = disp_y
boundary = 1
value = 0.0
[../]
[./botx2]
type = DirichletBC
variable = disp_x
boundary = 2
value = 0.0
[../]
[./boty2]
type = DirichletBC
variable = disp_y
boundary = 2
value = 0.0
[../]
[./topx]
type = FunctionDirichletBC
variable = disp_x
boundary = 4
function = horizontal_movement
[../]
[./topy]
type = DirichletBC
variable = disp_y
boundary = 4
value = -0.005
[../]
[]
[Materials]
[./bottom]
type = ComputeIsotropicElasticityTensor
block = '1'
youngs_modulus = 1.0e9
poissons_ratio = 0.3
[../]
[./top]
type = ComputeIsotropicElasticityTensor
block = '2'
youngs_modulus = 1.0e6
poissons_ratio = 0.3
[../]
[./stress]
type = ComputeFiniteStrainElasticStress
block = '1 2'
[../]
[]
[Postprocessors]
[./bot_react_x]
type = NodalSum
variable = saved_x
boundary = 1
[../]
[./bot_react_y]
type = NodalSum
variable = saved_y
boundary = 1
[../]
[./top_react_x]
type = NodalSum
variable = saved_x
boundary = 4
[../]
[./top_react_y]
type = NodalSum
variable = saved_y
boundary = 4
[../]
[./ref_resid_x]
type = NodalL2Norm
execute_on = timestep_end
variable = saved_x
[../]
[./ref_resid_y]
type = NodalL2Norm
execute_on = timestep_end
variable = saved_y
[../]
[]
[Executioner]
type = Transient
solve_type = 'PJFNK'
petsc_options_iname = '-pc_type -pc_factor_mat_solver_type'
petsc_options_value = 'lu superlu_dist'
petsc_options = '-mat_superlu_dist_iterrefine -mat_superlu_dist_replacetinypivot'
line_search = 'none'
l_max_its = 100
nl_max_its = 200
dt = 0.001
end_time = 0.01
num_steps = 1000
nl_rel_tol = 1e-8
nl_abs_tol = 1e-8
dtmin = 0.001
l_tol = 1e-3
[]
[Outputs]
exodus = true
print_linear_residuals = true
perf_graph = true
[./console]
type = Console
max_rows = 5
[../]
[]
[Contact]
[./leftright]
primary = 2
secondary = 3
model = coulomb
friction_coefficient = '0.25'
[../]
[]
[Dampers]
[./contact_slip]
type = ContactSlipDamper
primary = '2'
secondary = '3'
[../]
[]
(modules/combined/test/tests/break_mesh_interface_contact/break_mesh_interface_contact.i)
[GlobalParams]
order = FIRST
family = LAGRANGE
displacements = 'disp_x disp_y'
volumetric_locking_correction = true
[]
[Mesh]
[gen]
type = GeneratedMeshGenerator
nx = 5
ny = 5
dim = 2
[]
[block1]
type = SubdomainBoundingBoxGenerator
block_id = 1
bottom_left = '0 0 0'
top_right = '0.5 1 0'
input = gen
[]
[block2]
type = SubdomainBoundingBoxGenerator
block_id = 2
bottom_left = '0.5 0 0'
top_right = '1 1 0'
input = block1
[]
[breakmesh]
input = block2
type = BreakMeshByBlockGenerator
block_pairs = '1 2'
split_interface = true
add_interface_on_two_sides = true
[]
[]
[Variables]
[temperature]
[]
[disp_x]
[]
[disp_y]
[]
[]
[Kernels]
[thermal_cond]
type = HeatConduction
variable = temperature
[]
[]
[Physics/SolidMechanics/QuasiStatic]
generate_output = 'stress_xx stress_yy strain_xx strain_yy'
add_variables = true
strain = FINITE
incremental = true
[block1]
block = 1
[]
[block2]
block = 2
[]
[]
[ThermalContact]
[thermal_contact]
type = GapHeatTransfer
variable = temperature
primary = Block1_Block2
secondary = Block2_Block1
emissivity_primary = 0
emissivity_secondary = 0
quadrature = true
gap_conductivity = 1
[]
[]
[Contact]
[mechanical]
primary = Block1_Block2
secondary = Block2_Block1
penalty = 1000
model = coulomb
friction_coefficient = 0.5
formulation = tangential_penalty
tangential_tolerance = 0.1
[]
[]
[BCs]
[left_temp]
type = DirichletBC
value = 100
variable = temperature
boundary = left
[]
[right_temp]
type = DirichletBC
value = 0
variable = temperature
boundary = right
[]
[left_disp_x]
type = FunctionDirichletBC
variable = disp_x
boundary = left
function = 0
[]
[left_disp_y]
type = DirichletBC
variable = disp_y
boundary = left
value = 0.0
[]
[right_disp_x]
type = FunctionDirichletBC
variable = disp_x
boundary = right
function = '-t'
[]
[right_disp_y]
type = FunctionDirichletBC
variable = disp_y
boundary = right
function = '0'
[]
[]
[Materials]
[thermal_cond]
type = GenericConstantMaterial
prop_names = 'thermal_conductivity'
prop_values = 1
[]
[elasticity_tensor]
type = ComputeIsotropicElasticityTensor
poissons_ratio = 0.3
youngs_modulus = 100
[]
[stress]
type = ComputeFiniteStrainElasticStress
[]
[]
[Preconditioning]
[smp]
type = SMP
full = true
[]
[]
[Dampers]
[contact_slip]
type = ContactSlipDamper
secondary = Block1_Block2
primary = Block2_Block1
[]
[]
[Executioner]
type = Transient
solve_type = 'PJFNK'
petsc_options_iname = '-pc_type -pc_factor_mat_solver_type'
petsc_options_value = 'lu mumps'
line_search = none
nl_rel_tol = 1e-9
nl_abs_tol = 1e-9
l_tol = 1e-4
l_max_its = 50
nl_max_its = 20
start_time = 0.0
num_steps = 2
dtmin = 1e-8
dt = 1e-2
automatic_scaling = true
[]
[Outputs]
print_linear_residuals = false
time_step_interval = 1
csv = false
perf_graph = false
exodus = true
[]
(modules/contact/test/tests/hertz_spherical/hertz_contact_hex20.i)
# Hertz Contact: Sphere on sphere
# Spheres have the same radius, Young's modulus, and Poisson's ratio.
# Define E:
# 1/E = (1-nu1^2)/E1 + (1-nu2^2)/E2
#
# Effective radius R:
# 1/R = 1/R1 + 1/R2
#
# F is the applied compressive load.
#
# Area of contact a::
# a^3 = 3FR/4E
#
# Depth of indentation d:
# d = a^2/R
#
#
# Let R1 = R2 = 2. Then R = 1.
#
# Let nu1 = nu2 = 0.25, E1 = E2 = 1.40625e7. Then E = 7.5e6.
#
# Let F = 10000. Then a = 0.1, d = 0.01.
#
[GlobalParams]
volumetric_locking_correction = false
displacements = 'disp_x disp_y disp_z'
order = SECOND
[]
[Mesh]#Comment
file = hertz_contact_hex20.e
allow_renumbering = false
[] # Mesh
[Problem]
type = ReferenceResidualProblem
extra_tag_vectors = 'ref'
reference_vector = 'ref'
[]
[Functions]
[./pressure]
type = PiecewiseLinear
x = '0. 1. 2.'
y = '0. 1. 1.'
scale_factor = 795.77471545947674 # 10000/pi/2^2
[../]
[./disp_y]
type = PiecewiseLinear
x = '0. 1. 2.'
y = '0. -0.01 -0.01'
[../]
[] # Functions
[Variables]
[./disp_x]
order = SECOND
family = LAGRANGE
[../]
[./disp_y]
order = SECOND
family = LAGRANGE
[../]
[./disp_z]
order = SECOND
family = LAGRANGE
[../]
[] # Variables
[AuxVariables]
[./stress_xx]
order = CONSTANT
family = MONOMIAL
[../]
[./stress_yy]
order = CONSTANT
family = MONOMIAL
[../]
[./stress_zz]
order = CONSTANT
family = MONOMIAL
[../]
[./stress_xy]
order = CONSTANT
family = MONOMIAL
[../]
[./stress_yz]
order = CONSTANT
family = MONOMIAL
[../]
[./stress_zx]
order = CONSTANT
family = MONOMIAL
[../]
[./vonmises]
order = CONSTANT
family = MONOMIAL
[../]
[./hydrostatic]
order = CONSTANT
family = MONOMIAL
[../]
[./saved_x]
[../]
[./saved_y]
[../]
[./saved_z]
[../]
[] # AuxVariables
[Physics/SolidMechanics/QuasiStatic]
[./all]
add_variables = true
strain = SMALL
extra_vector_tags = 'ref'
save_in = 'saved_x saved_y saved_z'
[../]
[]
[AuxKernels]
[./stress_xx]
type = RankTwoAux
rank_two_tensor = stress
index_i = 0
index_j = 0
variable = stress_xx
[../]
[./stress_yy]
type = RankTwoAux
rank_two_tensor = stress
index_i = 1
index_j = 1
variable = stress_yy
[../]
[./stress_zz]
type = RankTwoAux
rank_two_tensor = stress
index_i = 2
index_j = 2
variable = stress_zz
[../]
[./stress_xy]
type = RankTwoAux
rank_two_tensor = stress
index_i = 0
index_j = 1
variable = stress_xy
[../]
[./stress_yz]
type = RankTwoAux
rank_two_tensor = stress
index_i = 1
index_j = 2
variable = stress_yz
[../]
[./stress_zx]
type = RankTwoAux
rank_two_tensor = stress
index_i = 2
index_j = 0
variable = stress_zx
[../]
# [./vonmises]
# type = RankTwoScalarAux
# rank_two_tensor = stress
# variable = vonmises
# scalar_type = VonMisesStress
# [../]
[] # AuxKernels
[BCs]
[./base_x]
type = DirichletBC
variable = disp_x
boundary = 1000
value = 0.0
[../]
[./base_y]
type = DirichletBC
variable = disp_y
boundary = 1000
value = 0.0
[../]
[./base_z]
type = DirichletBC
variable = disp_z
boundary = 1000
value = 0.0
[../]
[./symm_x]
type = DirichletBC
variable = disp_x
boundary = 1
value = 0.0
[../]
[./symm_z]
type = DirichletBC
variable = disp_z
boundary = 3
value = 0.0
[../]
[./disp_y]
type = FunctionDirichletBC
variable = disp_y
boundary = 2
function = disp_y
[../]
[] # BCs
[Contact]
[./dummy_name]
primary = 1000
secondary = 100
normalize_penalty = true
tangential_tolerance = 1e-3
penalty = 1e+10
[../]
[]
#[Dampers]
# [./contact_slip]
# type = ContactSlipDamper
# primary = 1000
# secondary = 100
# [../]
#[]
[Materials]
[./tensor]
type = ComputeIsotropicElasticityTensor
block = '1'
youngs_modulus = 1.40625e7
poissons_ratio = 0.25
[../]
[./stress]
type = ComputeLinearElasticStress
block = '1'
[../]
[./tensor_1000]
type = ComputeIsotropicElasticityTensor
block = '1000'
youngs_modulus = 1e6
poissons_ratio = 0.0
[../]
[./stress_1000]
type = ComputeLinearElasticStress
block = '1000'
[../]
[] # Materials
[Preconditioning]
[./SMP]
type = SMP
full = true
[]
[]
[Executioner]
type = Transient
solve_type = 'PJFNK'
petsc_options_iname = '-pc_type -pc_factor_mat_solver_type'
petsc_options_value = 'lu superlu_dist'
line_search = 'none'
nl_abs_tol = 1e-7
l_max_its = 10
start_time = 0.0
dt = 0.05
end_time = 2.0
[./Quadrature]
order = THIRD
[../]
[] # Executioner
[Postprocessors]
[./maxdisp]
type = NodalVariableValue
nodeid = 386 # 387-1 where 387 is the exodus node number of the top-center node
variable = disp_y
[../]
[./bot_react_x]
type = NodalSum
variable = saved_x
boundary = 2
[../]
[./bot_react_y]
type = NodalSum
variable = saved_y
boundary = 2
[../]
[./bot_react_z]
type = NodalSum
variable = saved_z
boundary = 2
[../]
[]
[Outputs]
[./out]
type = Exodus
elemental_as_nodal = true
[../]
[] # Outputs
(modules/contact/examples/2d_indenter/indenter_rz_nodeface_friction.i)
[GlobalParams]
volumetric_locking_correction = true
displacements = 'disp_x disp_y'
[]
[Problem]
type = ReferenceResidualProblem
reference_vector = 'ref'
extra_tag_vectors = 'ref'
[]
[Mesh]#Comment
file = indenter_rz_fine.e
displacements = 'disp_x disp_y'
# For NodalVariableValue to work with distributed mesh
allow_renumbering = false
coord_type = RZ
[] # Mesh
[Functions]
[./disp_y]
type = PiecewiseLinear
x = '0. 1.0 1.8 2. 3.0'
y = '0. -4.5 -5.4 -5.4 -4.0'
[../]
[] # Functions
[Variables]
[./disp_x]
order = FIRST
family = LAGRANGE
[../]
[./disp_y]
order = FIRST
family = LAGRANGE
[../]
[] # Variables
[AuxVariables]
[saved_x]
[]
[saved_y]
[]
[]
[Physics/SolidMechanics/QuasiStatic]
[./all]
add_variables = true
strain = FINITE
block = '1 2'
use_automatic_differentiation = false
generate_output = 'stress_xx stress_xy stress_xz stress_yy stress_zz'
save_in = 'saved_x saved_y'
[../]
[]
[AuxKernels]
[] # AuxKernels
[BCs]
# Symmetries of the Problem
[./symm_x_indenter]
type = DirichletBC
variable = disp_x
boundary = 5
value = 0.0
[../]
[./symm_x_material]
type = DirichletBC
variable = disp_x
boundary = 9
value = 0.0
[../]
# Material should not fly away
[./material_base_y]
type = DirichletBC
variable = disp_y
boundary = 8
value = 0.0
[../]
# Drive indenter motion
[./disp_y]
type = FunctionDirichletBC
variable = disp_y
boundary = 1
function = disp_y
[../]
[] # BCs
[Contact]
[./dummy_name]
primary = 6
secondary = 4
model = coulomb
formulation = penalty
normalize_penalty = true
friction_coefficient = 0.5
penalty = 8e6
tangential_tolerance = 0.005
[../]
[]
[Dampers]
[./contact_slip]
type = ContactSlipDamper
secondary = 4
primary = 6
[../]
[]
[Materials]
[./tensor]
type = ComputeIsotropicElasticityTensor
block = '1'
youngs_modulus = 1.0e7
poissons_ratio = 0.25
[../]
[./stress]
type = ComputeFiniteStrainElasticStress
block = '1'
[../]
[./tensor_2]
type = ComputeIsotropicElasticityTensor
block = '2'
youngs_modulus = 1e6
poissons_ratio = 0.0
[../]
[./power_law_hardening]
type = IsotropicPowerLawHardeningStressUpdate
strength_coefficient = 1e5 #K
strain_hardening_exponent = 0.5 #n
block = '2'
[../]
[./radial_return_stress]
type = ComputeMultipleInelasticStress
inelastic_models = 'power_law_hardening'
tangent_operator = elastic
block = '2'
[../]
[]
[Preconditioning]
[./SMP]
type = SMP
full = true
[]
[]
[Executioner]
type = Transient
solve_type = 'PJFNK'
petsc_options = '-snes_ksp_ew'
petsc_options_iname = '-pc_type -snes_linesearch_type -pc_factor_shift_type -pc_factor_shift_amount'
petsc_options_value = 'lu basic NONZERO 1e-15'
line_search = 'none'
automatic_scaling = true
nl_abs_tol = 1.5e-07
nl_rel_tol = 1.5e-07
l_max_its = 40
start_time = 0.0
dt = 0.025
end_time = 3.0
[]
[Postprocessors]
[./maxdisp]
type = NodalVariableValue
nodeid = 39 # 40-1 where 40 is the exodus node number
variable = disp_y
[../]
[resid_y]
type = NodalSum
variable = saved_y
boundary = 1
[]
[]
[Outputs]
[./out]
type = Exodus
elemental_as_nodal = true
[../]
perf_graph = true
csv = true
[]
(modules/contact/test/tests/frictional/sliding_elastic_blocks_2d/sliding_elastic_blocks_2d.i)
[Mesh]
file = sliding_elastic_blocks_2d.e
[]
[GlobalParams]
volumetric_locking_correction = false
displacements = 'disp_x disp_y'
[]
[AuxVariables]
[./penetration]
[../]
[./saved_x]
[../]
[./saved_y]
[../]
[./diag_saved_x]
[../]
[./diag_saved_y]
[../]
[./inc_slip_x]
[../]
[./inc_slip_y]
[../]
[./accum_slip_x]
[../]
[./accum_slip_y]
[../]
[./accum_slip]
[../]
[./tang_force_x]
[../]
[./tang_force_y]
[../]
[]
[Functions]
[./vertical_movement]
type = ParsedFunction
expression = -t
[../]
[]
[Physics/SolidMechanics/QuasiStatic]
[./all]
add_variables = true
strain = FINITE
save_in = 'saved_x saved_y'
diag_save_in = 'diag_saved_x diag_saved_y'
[../]
[]
[AuxKernels]
[./inc_slip_x]
type = PenetrationAux
variable = inc_slip_x
quantity = incremental_slip_x
boundary = 3
paired_boundary = 2
[../]
[./inc_slip_y]
type = PenetrationAux
variable = inc_slip_y
quantity = incremental_slip_y
boundary = 3
paired_boundary = 2
[../]
[./accum_slip]
type = PenetrationAux
variable = accum_slip
execute_on = timestep_end
quantity = accumulated_slip
boundary = 3
paired_boundary = 2
[../]
[./tangential_force_x]
type = PenetrationAux
variable = tang_force_x
execute_on = timestep_end
quantity = tangential_force_x
boundary = 3
paired_boundary = 2
[../]
[./tangential_force_y]
type = PenetrationAux
variable = tang_force_y
execute_on = timestep_end
quantity = tangential_force_y
boundary = 3
paired_boundary = 2
[../]
[./accum_slip_x]
type = AccumulateAux
variable = accum_slip_x
accumulate_from_variable = inc_slip_x
execute_on = timestep_end
[../]
[./accum_slip_y]
type = AccumulateAux
variable = accum_slip_y
accumulate_from_variable = inc_slip_y
execute_on = timestep_end
[../]
[./penetration]
type = PenetrationAux
variable = penetration
boundary = 3
paired_boundary = 2
[../]
[]
[Postprocessors]
[./bot_react_x]
type = NodalSum
variable = saved_x
boundary = 1
[../]
[./bot_react_y]
type = NodalSum
variable = saved_y
boundary = 1
[../]
[./top_react_x]
type = NodalSum
variable = saved_x
boundary = 4
[../]
[./top_react_y]
type = NodalSum
variable = saved_y
boundary = 4
[../]
[./ref_resid_x]
type = NodalL2Norm
execute_on = timestep_end
variable = saved_x
[../]
[./ref_resid_y]
type = NodalL2Norm
execute_on = timestep_end
variable = saved_y
[../]
[]
[BCs]
[./left_x]
type = DirichletBC
variable = disp_x
boundary = 1
value = 0.0
[../]
[./left_y]
type = DirichletBC
variable = disp_y
boundary = 1
value = 0.0
[../]
[./right_x]
type = DirichletBC
variable = disp_x
boundary = 4
value = -0.005
[../]
[./right_y]
type = FunctionDirichletBC
variable = disp_y
boundary = 4
function = vertical_movement
[../]
[]
[Materials]
[./left]
type = ComputeIsotropicElasticityTensor
block = '1'
youngs_modulus = 1.0e7
poissons_ratio = 0.3
[../]
[./right]
type = ComputeIsotropicElasticityTensor
block = '2'
youngs_modulus = 1.0e6
poissons_ratio = 0.3
[../]
[./stress]
type = ComputeFiniteStrainElasticStress
block = '1 2'
[../]
[]
[Preconditioning]
[./SMP]
type = SMP
full = true
[../]
[]
[Executioner]
type = Transient
solve_type = 'PJFNK'
petsc_options_iname = '-pc_type -pc_factor_mat_solver_type'
petsc_options_value = 'lu superlu_dist'
line_search = 'none'
l_max_its = 100
nl_max_its = 1000
dt = 0.01
end_time = 0.05
num_steps = 1000
nl_rel_tol = 1e-16
nl_abs_tol = 1e-09
dtmin = 0.01
l_tol = 1e-3
[./Predictor]
type = SimplePredictor
scale = 1.0
[../]
[]
[Outputs]
file_base = sliding_elastic_blocks_2d_out
print_linear_residuals = true
perf_graph = true
[./exodus]
type = Exodus
elemental_as_nodal = true
[../]
[./console]
type = Console
max_rows = 5
[../]
[]
[Contact]
[./leftright]
secondary = 3
primary = 2
model = coulomb
friction_coefficient = '0.25'
penalty = 1e6
[../]
[]
[Dampers]
[./contact_slip]
type = ContactSlipDamper
secondary = 3
primary = 2
[../]
[]
(modules/contact/test/tests/verification/patch_tests/single_pnt_2d/single_point_2d_frictional.i)
[GlobalParams]
volumetric_locking_correction = true
displacements = 'disp_x disp_y'
[]
[Mesh]
file = single_point_2d.e
[]
[Variables]
[./disp_x]
[../]
[./disp_y]
[../]
[]
[AuxVariables]
[./penetration]
[../]
[./saved_x]
[../]
[./saved_y]
[../]
[./diag_saved_x]
[../]
[./diag_saved_y]
[../]
[./inc_slip_x]
[../]
[./inc_slip_y]
[../]
[./accum_slip_x]
[../]
[./accum_slip_y]
[../]
[]
[Functions]
[./appl_disp]
type = PiecewiseLinear
x = '0 0.001 0.101'
y = '0 0.0 -0.10'
[../]
[]
[Kernels]
[./TensorMechanics]
use_displaced_mesh = true
save_in = 'saved_x saved_y'
[../]
[]
[AuxKernels]
[./incslip_x]
type = PenetrationAux
variable = inc_slip_x
quantity = incremental_slip_x
boundary = 3
paired_boundary = 2
[../]
[./incslip_y]
type = PenetrationAux
variable = inc_slip_y
quantity = incremental_slip_y
boundary = 3
paired_boundary = 2
[../]
[./accum_slip_x]
type = AccumulateAux
variable = accum_slip_x
accumulate_from_variable = inc_slip_x
execute_on = timestep_end
[../]
[./accum_slip_y]
type = AccumulateAux
variable = accum_slip_y
accumulate_from_variable = inc_slip_y
execute_on = timestep_end
[../]
[./penetration]
type = PenetrationAux
variable = penetration
boundary = 3
paired_boundary = 2
[../]
[]
[BCs]
[./botx]
type = DirichletBC
variable = disp_x
boundary = 1
value = 0.0
[../]
[./boty]
type = DirichletBC
variable = disp_y
boundary = 1
value = 0.0
[../]
[./topx]
type = FunctionDirichletBC
variable = disp_x
boundary = 4
function = appl_disp
[../]
[./topy]
type = DirichletBC
variable = disp_y
boundary = 4
value = -0.002001
[../]
[]
[Materials]
[./bot_elas_tens]
type = ComputeIsotropicElasticityTensor
block = '1'
youngs_modulus = 1e9
poissons_ratio = 0.3
[../]
[./bot_strain]
type = ComputePlaneFiniteStrain
block = '1'
[../]
[./bot_stress]
type = ComputeFiniteStrainElasticStress
block = '1'
[../]
[./top_elas_tens]
type = ComputeIsotropicElasticityTensor
block = '2'
youngs_modulus = 1e6
poissons_ratio = 0.3
[../]
[./top_strain]
type = ComputePlaneFiniteStrain
block = '2'
[../]
[./top_stress]
type = ComputeFiniteStrainElasticStress
block = '2'
[../]
[]
[Postprocessors]
[./bot_react_x]
type = NodalSum
variable = saved_x
boundary = 1
[../]
[./bot_react_y]
type = NodalSum
variable = saved_y
boundary = 1
[../]
[./top_react_x]
type = NodalSum
variable = saved_x
boundary = 4
[../]
[./top_react_y]
type = NodalSum
variable = saved_y
boundary = 4
[../]
[./disp_x]
type = NodalVariableValue
nodeid = 5
variable = disp_x
[../]
[./disp_y]
type = NodalVariableValue
nodeid = 5
variable = disp_y
[../]
[./inc_slip_x]
type = NodalVariableValue
nodeid = 5
variable = inc_slip_x
[../]
[./inc_slip_y]
type = NodalVariableValue
nodeid = 5
variable = inc_slip_y
[../]
[./accum_slip_x]
type = NodalVariableValue
nodeid = 5
variable = accum_slip_x
[../]
[./accum_slip_y]
type = NodalVariableValue
nodeid = 5
variable = accum_slip_y
[../]
[]
[Executioner]
type = Transient
solve_type = 'PJFNK'
petsc_options_iname = '-pc_type -pc_factor_mat_solver_type'
petsc_options_value = 'lu superlu_dist'
line_search = 'none'
l_max_its = 100
nl_max_its = 200
dt = 0.001
end_time = 0.001
num_steps = 10000
nl_rel_tol = 1e-6
nl_abs_tol = 1e-8
dtmin = 0.001
l_tol = 1e-3
[]
[Outputs]
file_base = single_point_2d_out_frictional_0_2_kin
print_linear_residuals = true
perf_graph = true
csv = true
[./console]
type = Console
max_rows = 5
[../]
[]
[Contact]
[./leftright]
primary = 2
secondary = 3
model = coulomb
formulation = kinematic
penalty = 1e12
normalize_penalty = true
friction_coefficient = '0.2'
tangential_tolerance = 1e-3
[../]
[]
[Dampers]
[./contact_slip]
type = ContactSlipDamper
primary = '2'
secondary = '3'
[../]
[]